ToolSphere

PCB Trace Width Calculator

Electronics

IPC-2221 PCB trace width in mm and mil for outer and inner layers, max current for an existing trace, and the trace's resistance, voltage drop and loss.

Trace
Width
0.7814 mm
Width
30.76 mil
Cross-section
42.39 mil²

Round up to your fab's width grid, and add margin if the trace runs near heat sources or other high-current traces.

Resistance, drop and loss
Resistance
33.38 mΩ
Voltage drop
66.75 mV
Power loss
133.5 mW

For the width above, at ambient + rise. Copper resistance rises about 0.39% per °C.

How much current can a trace carry?
Max current for 10 °C rise
1.45 A

19.69 mil, same layer and copper weight as above.

On this browser only

Give feedback

Did this tool help?

Tell us what worked, what didn’t, or what you’d like next.

Opens Google Forms in a new tab with this tool’s name filled in. No sign-in or email required. Feedback is optional.

How to use PCB Trace Width Calculator

  1. 1Choose outer or inner copper and enter positive current, allowed temperature rise and copper weight.
  2. 2Read the calculated width in mm and mil and the cross-sectional area. Review any extrapolation warnings before using the estimate.
  3. 3Enter trace length and ambient temperature to calculate resistance, drop and loss at ambient plus the chosen rise.
  4. 4Enter an existing width in millimeters to estimate its current for the same layer, copper weight and temperature rise.
  5. 5Round upward to a manufacturable width and check stackup, bottlenecks, return path and voltage-drop budget separately.

About PCB Trace Width Calculator

Estimate PCB trace width and current capacity

This PCB trace width calculator uses the IPC-2221 curve-fit equation to estimate a conductor width from current, copper thickness, layer and allowed temperature rise. It shows both millimeters and mils, with cross-sectional area in square mils. A second panel estimates DC resistance, voltage drop and power loss along the calculated width; a third evaluates an existing width using the same thermal assumptions.

Use the result as an initial layout estimate for a power rail or load connection. A thermal width does not establish signal impedance, electrical clearance or complete board reliability. Trace temperature depends on the actual board and its surroundings, so a numerical result is not a substitute for checking your stackup and testing the finished design.

The implemented formula and units

The model is I = k × ΔT^0.44 × A^0.725. Current I is in amperes, ΔT is the rise above ambient in °C, and A is cross-sectional area in square mils. The implemented coefficient k is 0.048 for outer copper and 0.024 for inner copper. Solving for area gives A = (I / (k × ΔT^0.44))^(1/0.725).

Width is area divided by copper thickness. The calculator treats one ounce per square foot as approximately 35 µm, or 1.378 mil, of copper thickness. It converts between millimeters and mils using 25.4 mm per inch. A mil is a thousandth of an inch; it is not a millimeter. Cross-sectional area also differs from the visible top-view area of the track.

Copper weight is selectable independently of layer. Verify whether the fabrication specification describes starting foil or finished copper, and use the manufacturer's actual thickness information when evaluating a production board. The interface models a uniform rectangular trace, not a changing plated cross-section or an irregular copper polygon.

Worked example: an outer-layer power trace

Select outer layer, enter 3 A, allow a 10 °C rise and choose 1 oz copper. The library returns the following results. For the resistance panel, use an 80 mm trace and 25 °C ambient, so its modeled operating temperature is 35 °C.

Calculated quantity Result
Cross-sectional area 74.1616 mil²
Required width 53.8183 mil
Required width in metric 1.36699 mm
Resistance over the entered length 30.5261 mΩ
Voltage drop at the entered current 91.5782 mV
Dissipated power 274.735 mW

The interface rounds these quantities for display. Choose a fabrication width at or above the estimate and consider additional margin for the real thermal environment. Even if temperature rise is acceptable, the voltage drop may exceed your rail budget. The return conductor contributes its own resistance and drop; the length field describes the trace being calculated, not an automatically included complete current loop.

Compare outer and inner layers

For 1 oz copper and a 10 °C rise, the implemented curve produces these widths:

Current Outer width, mm Inner width, mm
0.5 A 0.1155 0.3004
1 A 0.3004 0.7814
2 A 0.7814 2.0328
3 A 1.3670 3.5561
5 A 2.7654 7.1941

These are calculated values under the stated assumptions, not universal trace ratings. In this model, doubling copper thickness halves the required width for a fixed current and temperature rise. A higher allowed rise also reduces the required width, but increases conductor temperature. Choose the temperature budget from component and material requirements rather than increasing it simply to make a trace fit.

Check an existing width separately

The existing-width panel runs the equation forward to estimate current at the selected rise. An outer 10 mil trace in 1 oz copper gives about 0.8855 A at a 10 °C rise. A 0.5 mm trace under the same conditions gives about 1.4469 A. The panel accepts millimeters, so convert a mil dimension before entering it.

This existing-width field does not replace the width used by the resistance panel. Resistance, voltage drop and loss still refer to the calculated required width above. Keep those panels distinct when comparing a planned trace against an existing layout. The inverse estimate also inherits the underlying curve's limitations; changing the direction of calculation does not validate an unsuitable thermal model.

Resistance and voltage-drop interpretation

The loss calculation uses R = ρ × length / cross-sectional area, with a linear temperature adjustment for copper resistivity. Voltage drop is I × R and loss is I² × R. Ambient plus the selected rise sets the conductor temperature used for this estimate. Ambient temperature can be below zero, while an empty field means the temperature has not been supplied.

Length changes the calculated loss and drop, but does not change the thermal width equation. The model does not solve heat flow along a complete routed board. Pads, neck-downs, connectors, vias, solder joints and the return path need their own checks. A wide track with a narrow bottleneck cannot be judged from the wide section alone.

Extrapolation and detailed thermal design

The tool warns outside its configured curve ranges, including large currents, widths, copper weights and temperature rises. Warnings identify extrapolation; they do not make an extrapolated result accurate. Likewise, no warning does not prove that the board's actual cooling matches the simplified model.

IPC-2152 addresses current-carrying capacity in printed-board design with broader thermal design context. This calculator does not implement that standard's detailed approach. Do not assume that the legacy inner/outer coefficient alone describes the behavior of every board, or that one layer's calculated width is automatically suitable for another stackup.

Continue the power-path checks

Use the Ohm's law calculator to compare load, voltage and power requirements. The AWG wire calculator provides a separate starting point for external copper wiring. For a component heat path, use the thermal resistance calculator. The PCB trace-width worked example provides another calculation walkthrough. None of these checks replaces the others: conductor heating, component temperature and acceptable supply drop can impose different design limits.

Guides and tutorials

Frequently asked questions

How wide should a PCB trace be for one amp?

For the implemented outer-layer model with 1 oz copper and a 10 °C rise, the calculated width is about 0.3004 mm. Change the layer, copper thickness or temperature allowance and the answer changes; round upward and check the actual board conditions.

Does this use IPC-2221 or IPC-2152?

It uses the IPC-2221 current/area curve-fit equation. It does not implement the more detailed board-dependent thermal design approach associated with IPC-2152.

What is the difference between a mil and a millimeter?

A mil is a thousandth of an inch, while a millimeter is a metric length. The required-width result shows both; the existing-width input explicitly expects millimeters.

What does temperature rise mean in a trace calculator?

It is the allowed conductor temperature increase above ambient, not the ambient temperature itself. The resistance estimate uses ambient plus that rise as its modeled copper temperature.

Why does the inner-layer setting give a wider trace?

The implemented legacy equation uses a smaller coefficient for inner layers. Actual heat spreading depends on the stackup and nearby copper, so the coefficient difference is a model assumption rather than a universal cooling rule.

Does doubling copper weight halve the required width?

Yes, within this equation and at the same current and temperature rise, because the required cross-sectional area stays the same. Check the fabricator’s actual finished copper thickness before treating nominal copper weight as exact.

Can I calculate current for an existing PCB trace?

Yes; enter its width in the existing-width panel using millimeters. That estimate shares the selected layer, copper weight and rise, but it does not change the width used in the separate resistance calculation.

Why does trace length change drop but not the required width?

Length enters the DC resistance calculation, while the thermal width estimate uses current, copper, layer and rise. This simplified model does not compute the full board’s heat flow or total circuit-loop resistance.

Does this calculator size vias or controlled-impedance traces?

No; it models a uniform copper trace for heating and DC loss. Via barrels, transient behavior, clearances and controlled impedance require different geometry and analysis.

Is a result without warnings guaranteed to work?

No; the warnings only identify selected extrapolation conditions. Nearby heat sources, restricted cooling, neck-downs and the actual stackup still need engineering review and appropriate verification.

Have a suggestion for PCB Trace Width Calculator?Share your feedback ↗